Donny Don’t – Remote Objects

By: Doug Oatis
– January 27, 2015
Categories:

Nothing like a good ‘ol fashion Simpson’s reference.  I’m trying to start a new series of articles that address common mistakes and things to avoid, and what better reference than when Bart ‘joined’ the Junior Campers and found out he might get a knife out of the deal. 

6lrWlDO

For this first article, let’s talk about remote objects (force, displacement, points, joints).  First, remote objects are awesome.  Want to add a rotational DOF to your solid-object model?  Remote Displacement.  Want to apply a load and don’t want to worry about force/moment balance?  Remote Force.  Want to apply a load but also constrain a surface?  Remote Point.  Take two points and define a open/locked degrees of freedom and you have a kinematic joint.

The thing to watch out for is how you define these remote points.  ANSYS Mechanical does an amazing job at making a pretty tedious process easy (create pilot node, create constraint-type contact, specify DOFs to include, specify formulation).  In Mechanical, all you need to do is highlight some geometry, right mouse click, and insert the appropriate object (remote point, remote force, etc).  No need to keep track of real constant sets, element tshape’s…easy.  Almost too easy if you ask me.

Once you start creating multiple remote objects, you may see the following:

message1

If you dig into the solver output file you may see this:

image

The complaint is that we have multiple overlapping constraint sets.  Let’s take a step back and see the model I’ve setup:

image

I have a cylinder, attached to a body-to-ground spring on one face, a translational joint applied on the OD, and a remote force and moment applied on the opposite end.  If I follow the instructions shown from the ANSYS Workbench message about graphically displaying FE Connections (select the ‘Solution Information’ item, click the graphics tab):

image

We can see that any type of constraint equation is shown in red.  The issue here is that the nodes on the OD edge on the top and bottom of my cylinder belong to multiple constraint equation sets.  On the bottom my my cylinder those nodes are being constrained to the spring end AND the cylindrical joint.  On the top the nodes on the edge are being constrained to the joint AND remote force.  When you hit solve, ANSYS needs to figure out how to resolve the conflicting constraint sets (a node cannot be a slave term for two different constraint sets).  I don’t know exactly how the solver manages this, but I like to imagine it’s like two people fighting over who gets to keep a dog…and they place the dog in-between them and call for it, and whoever the dog goes to gets to keep it. 

Now for this example, the solver is capable of handling the over-constraint because overall…the model is properly constrained.  The spring can loose some of the edge nodes and still properly connect to the cylinder.  Same goes for the other remote objects (translation joint and remote force/moment).  If we had more objects defined and more overlaps, that’s a different story.  You can introduce a pretty lengthy lag, or outright solver failure, if there are a lot of overconstraint terms in the model. 

So now the question becomes, how do I fix this.  The easiest way is to not fix this and ignore the warning.  If our part behaves properly, we get the reaction forces we’d expect, then odds are the overconstraint terms that are automatically corrected are fine.  If we actually wanted to remove that warning, we would need to make sure we scope remote objects that do not touch other remote objects.  We can do this by going into DesignModeler or SpaceClaim and imprinting the surfaces. 

image

In DM, I just extruded the edges with the operation set to imprint face.  In SpaceClaim you would just need to use the ‘copy edge’ option on the pull command:

image

Now this will modify the topology and will ensure we have a separation of nodes for all of our remote objects:

image

When we solve…no warning message about MPC conflicts:

image

And when we look at the FE connectivity, there are no nodes shared by multiple remote objects:

image 

The last thing I’d like to point out is the application of a force and moment on a remote point:

image

Whenever you have two remote objects operating on the same surface (e.g. a moment and force, force and displacement, etc), you should really be using a remote point.  If I were to create two remote objects:

image

I now come right back to my original problem of conflicting constraints.  These two objects share the exact same nodal set but are creating two independent remote points.  If you want to do this, right-mouse-click on one of your remote objects and select ‘promote to remote point’:

image

Then modify the other remote objects to use that remote point.  No more conflict. 

Very last point…in R16 it will now tell you when you have ‘duplicate’ remote objects  (like the remote force + displacement shown above). 

image

Hope this helps! 

Categories

Certified Elite Channel Partner

Get Your Ansys Products & Support from the Engineers who Contribute to this Blog.

Product Development
Diamond Partner

Technical Expertise to Enable your Addictive Manufacturing Success.

PADT’s Pulse Newsletter

Keep up to date on what is going on at PADT by subscribing to our newsletter.


By submitting this form, you are consenting to receive marketing emails from: Phoenix Analysis and Design Technologies, 7755 S. Research Dr., Tempe, AZ, 85284, https://www.padtinc.com. You can revoke your consent to receive emails at any time by using the SafeUnsubscribe® link, found at the bottom of every email. Emails are serviced by Constant Contact

Share this post:

Share on twitter
Share on facebook
Share on linkedin
Share on pinterest

Upcoming Events

08/10/2022

Tucson after5 Tech Mixer: Ruda-Cardinal

08/05/2022

Flagstaff Tech Tour, 2022

08/02/2022

2022 CEO Leadership Retreat

08/01/2022

2022 CEO Leadership Retreat

07/27/2022

Thermal Integrity Updates in Ansys 2022 R1 - Webinar

07/20/2022

Simulation Best Practices for the Pharmaceutical Industry - Webinar

07/14/2022

NCMS Technology Showcase: Corpus Christi Army Depot

07/13/2022

NCMS Technology Showcase: Corpus Christi Army Depot

07/13/2022

Additive & Structural Optimization Updates in Ansys 2022 R1 - Webinar

07/07/2022

Arizona AADM Conference, 2022

06/29/2022

LS-DYNA Updates & Advancements in Ansys 2022 R1 - Webinar

06/23/2022

Simulation Best Practices for Wind Turbine Design - Webinar

06/15/2022

MAPDL Updates & Advancements in Ansys 2022 R1 - Webinar

06/01/2022

Mechanical Updates in Ansys 2022 R1 - pt. 2 Webinar

05/26/2022

Modelling liquid cryogenic rocket engines in Flownex - Webinar

05/25/2022

SMR & Advanced Reactor 2022

05/25/2022

05/24/2022

SMR & Advanced Reactor 2022

05/19/2022

RAPID + tct 2022

05/19/2022

Venture Cafe Roundtable: AI & Healthcare

05/18/2022

Tucson after5 Tech Mixer: World View

05/18/2022

RAPID + tct 2022

More Info

05/18/2022

Signal & Power Integrity Updates in Ansys 2022 R1 - Webinar

05/18/2022

Simulation World 2022

05/17/2022

RAPID + tct 2022

05/11/2022

Experience Stratasys Manufacturing Virtual Event

05/04/2022

Mechanical Meshing Updates in Ansys 2022 R1 - Webinar

04/27/2022

04/22/2022

12TH ANNUAL TUCSON GOLF TOURNAMENT

04/21/2022

04/20/2022

Additional Fluids Updates in Ansys 2022 R1

04/20/2022

Experience Stratasys Tour – Tempe Arizona

04/18/2022

Experience Stratasys Tour - Flagstaff Arizona

04/14/2022

D&M West | MD&M West

04/13/2022

D&M West | MD&M West

04/13/2022

Experience Stratasys Tour - Albuquerque New Mexico

04/12/2022

D&M West | MD&M West

04/12/2022

Experience Stratasys Tour - Los Alamos New Mexico

04/12/2022

Optimizing Engineering Workflows f​​​​or Propulsion System Design

04/07/2022

Experience Stratasys Tour - Austin Texas

04/07/2022

37th Space Symposium - Arizona Space Industry

04/06/2022

Transforming Digital Engineering with Ansys Discovery 2022 R1

04/06/2022

37th Space Symposium - Arizona Space Industry

04/05/2022

37th Space Symposium - Arizona Space Industry

04/04/2022

37th Space Symposium - Arizona Space Industry

03/30/2022

Simulation Best Practices for Vehicle Engineering - Webinar

03/23/2022

03/23/2022

High & Low Frequency Electromagnetics Updates in Ansys 2022 R1

02/24/2022

Arizona Technology Council After 5 Tech Mixer "Pandemic Pivot Pizza Pa

02/23/2022

SciTech Festival: Spend an Hour with 3D Printing Experts

02/11/2022

Webinar: Mechanical overview for Ansys 2022 R1

More Info

02/09/2022

Webinar: Product Development 101 (FAKE)

02/08/2022

Webinar: Navigating the Additive Landscape

01/27/2022

Arizona Technology Council 1st Quarter VIP Tech Mixer

More Info

01/26/2022

Simulation Best Practices for Gas Turbine Design & Development - Webin

More Info

01/19/2022

Arizona Photonics Days

More Info

11/04/2021

ExperienceIT, New Mexico

More Info

11/03/2021

Additive Manufacturing & Structural Optimization in Ansys 2021 R2 - We

More Info

11/03/2021

Optics Valley Technical Series: The Future of Simulation in the Optics

More Info

11/02/2021

SBIR Liftoff AZTC Virtual Breakfast Series

More Info

10/10/2021

Stratasys Mobile Truck Stop - Tucson Arizona

More Info

Search in PADT site

Contact Us

Most of our customers receive their support over the phone or via email. Customers who are close by can also set up a face-to-face appointment with one of our engineers.

For most locations, simply contact us: